首页 » 博客 » Technical Guides » Types of Holes in Engineering Drawings: Symbols, Callouts and Tolerances

Types of Holes in Engineering Drawings: Symbols, Callouts and Tolerances

目录

拓维精密

需要专业的机械加工解决方案吗?拓维模型的团队随时准备为您提供全方位的制造支持。立即联系我们,获取您正在进行或即将开展的项目的报价!

Types of holes in engineering - machined plate with through, blind, tapped, counterbored, countersunk and dowel holes

A drawing covered in circles is really a list of instructions: each hole’s symbol and callout tells the machinist exactly what to drill, bore, tap or ream — and what the hole must do in the assembly. Misread a ⌴ as a ⌵ and a cap screw sits proud of the surface. This guide covers every common hole type with its symbol, how to read and write callouts, plus the numeric data most guides skip: tap drill sizes, actual H7 tolerance values, and depth and edge-distance rules you can design to.

The Hole Types at a Glance

Hole type Symbol / callout 目的 Made by
Through hole ⌀6 THRU Clearance, wiring, flow 钻探
Blind hole ⌀6 ↧10 (depth symbol) Fastening without breakthrough Drilling to depth
Tapped (threaded) hole M6×1.0 – 6H ↧12 Screw engagement Drill + tap or thread mill
Counterbore ⌀6.6 THRU ⌴⌀11 ↧6.5 Recess socket head cap screws flush Counterbore tool / end mill
Countersink ⌀6.6 THRU ⌵⌀12.6×90° Seat flat-head screws flush Countersink cutter
Spotface SF⌀14 (shallow ⌴) Flat washer seat on rough/cast surface Shallow counterbore pass
Reamed hole ⌀8 H7 REAM Precision fit for pins, bushings, shafts Drill + ream
Dowel hole ⌀6 H7, position tol. Precise alignment between parts Drill + ream (often matched pairs)
Clearance hole ⌀6.6 for M6 Screw passes freely 钻探

Deep dive on the two most-confused recesses: counterbore vs countersink.

Reading a Callout, Layer by Layer

4× ⌀6.6 THRU ⌴⌀11.0 ↧6.5 reads: four holes, 6.6 mm diameter all the way through, counterbored to 11 mm diameter, counterbore 6.5 mm deep. Order is always smallest operation first (the pilot), then the recess. Thread callouts put size and pitch first: M6×1.0 – 6H ↧12, hole ↧15 — thread 12 mm deep in a hole drilled 15 mm deep (taps need runout room; thread mills don’t).

Clearance and Tap Drill Chart (Metric)

Thread Tap drill (75%) Close clearance Normal clearance SHCS c’bore ⌀×depth
M3×0.5 2.5 mm 3.2 mm 3.4 mm 6.5×3.4
M4×0.7 3.3 mm 4.3 mm 4.5 mm 8.0×4.6
M5×0.8 4.2 mm 5.3 mm 5.5 mm 9.5×5.7
M6×1.0 5.0 mm 6.4 mm 6.6 mm 11.0×6.8
M8×1.25 6.8 mm 8.4 mm 9.0 mm 14.0×9.0
M10×1.5 8.5 mm 10.5 mm 11.0 mm 17.5×11.0
M12×1.75 10.2 mm 13.0 mm 13.5 mm 19.5×13.0

Full UNC/UNF and pipe-thread data lives in our thread size chart.

Hole Tolerances in Actual Numbers

过程 Typical tolerance on ⌀ Example: ⌀10 hole
Drilled +0.05/+0.15, −0 10.00–10.15 mm, Ra 3.2–6.3
Reamed H7 IT7 10.000–10.015 mm, Ra 0.4–1.6
Bored IT6–IT9 + true position position correction possible
Honed IT5–IT6 10.000–10.009 mm, Ra 0.05–0.4

Common fits on a ⌀10 H7 hole: press-fit dowel (pin m6/p6 → 0.004–0.029 mm interference), slip-fit dowel (pin g6 → 0.005–0.029 mm clearance), bearing seat usually H7/k6 or tighter. When a hole needs both position and size precision, bore for location then ream for size; for sliding-seal bores, finish by honing.

Design Rules That Keep Holes Cheap

  • Depth: keep drilled depth ≤ 4× diameter where possible; 4–8× needs peck cycles (+time); beyond 10× needs gun drilling (+cost)
  • Edge distance: ≥ 1× diameter from any edge (centerline to edge ≥ 1.5×⌀ for loaded holes) or the wall bulges and the drill wanders
  • Hole-to-hole spacing: ≥ 1×⌀ web between holes; less risks breakthrough and burrs
  • Flat-bottom blind holes: specify only when needed (end mill, not drill — slower); otherwise allow the 118°/135° drill point
  • Angled entry/exit: avoid drilling into slopes; add a spotface or machine a flat first
  • Thread depth: more than 1.5×⌀ of engagement adds no strength in steel; specify ↧1.5×⌀ and save tap wear
  • Tolerance only what matters: an H7 callout on a clearance hole doubles its cost for nothing

常见问题

What are the different types of holes in engineering?

The core set: through, blind, tapped, clearance, counterbored, countersunk, spotfaced, reamed and dowel holes — plus specialized forms like tapered holes, gun-drilled deep holes, and jig-bored precision holes. Each has a distinct symbol and callout convention on drawings.

What do you call a hole that doesn’t go all the way through?

A blind hole. Its callout carries the depth symbol (↧ in ISO; “DEEP” or ⌳ historically in ASME): ⌀6 ↧10 means 6 mm diameter, 10 mm deep — measured to the full-diameter shoulder, not the drill point.

What is the difference between a counterbore and a spotface?

Geometry is identical; depth and purpose differ. A counterbore is deep enough to bury a fastener head; a spotface is a shallow clean-up (often 1–2 mm) that just gives a washer or bolt head a flat, perpendicular seat on a cast or rough surface. ASME marks spotface with SF inside the counterbore symbol.

When should a hole be reamed instead of drilled?

When the fit matters: dowel pins, bushings, bearing seats, hinge pins — anything specified H7 or tighter, or needing Ra below ~1.6 µm. Drilling alone holds roughly ±0.1 mm; reaming brings that to ±0.01 mm class.

Every Hole, To Spec

Drilled, tapped, reamed, bored or honed — hole quality is where precision parts pass or fail inspection. Our 数控加工服务 hold H7 fits and true-position callouts across turned parts and milled components alike, with full dimensional reports. Send your drawing for a 24-hour quote.

图为拓维模型的一名员工身穿蓝色Polo衫,站在工厂内背景模糊的数控机床前
关于作者
安迪

tuoweiprecision 制造工程师

作者:安迪,拓维模型制造工程师。. 安迪专攻数控加工、精密制造和生产工程领域,在从快速原型制作到大规模量产的整个项目过程中拥有丰富的实践经验。他与工程和制造团队紧密合作,共同评估材料、公差、加工工艺以及设计可制造性。 他的文章提供了实用且具有技术深度的见解,旨在帮助工程师和采购人员做出更明智的制造决策、优化生产效率,并确保零件质量的一致性。欢迎了解拓维模型的数控加工和定制制造解决方案,为您的下一个项目提供支持。.

让我们携手共创未来

与拓维模型携手,共同实现您的愿景

从快速原型制作到可扩展的生产,Tuowei Precision 提供可靠的数控加工服务,在每个环节都确保精度与一致性。立即启动您的项目。.

与我们联系!
保证在24小时内及时回复
🔐 所有上传内容均安全保密

探索洞察与创新

阅读我们关于数控加工、材料、表面处理及行业趋势的最新指南,以做出更明智的生产决策。

与我们联系!
保证在24小时内及时回复
🔐 所有上传内容均安全保密